Revision as of 19:47, 24 May 2018 (view source) Valdesjg (talk | contribs) ← Older edit	Revision as of 19:53, 24 May 2018 (view source) Valdesjg (talk | contribs) m (Valdesjg moved page Draft Valdes-Vazquez 941806245 to Review 729493725672) Newer edit →
(No difference)

---

Revision as of 19:53, 24 May 2018

Abstract

The seismic response of tensile membrane structures (TMS) is investigated. To the authors knowledge, this is the first study on TMSs subjected to a seismic record reported in the literature. A type of membrane structures usually considered as a reference in other works are employed in the present study. The selected hyperbolic-paraboloid fabric structures, also referred as hypar TMSs, are subjected to an earthquake accelerogram from a relatively large earthquake recorded at Norcia, Italy. To obtain the TMSs seismic response, a finite element formulation reported in a previous study, and which accounts for wrinkling phenomena, orthotropic material modeling, and geometrical nonlinearity, is employed. The analyses are performed in two stages; first for the prestressed case and then the seismic loading is added. It is found that the seismic response of TMSs should not be disregarded by designers beforehand, since important increments in the dynamic response of the displacements produce an incremet of around 9% for stresses. However, a very important increment of around 80% for support reaction forces is computed, when compared with the static case. It is also found that the orientation of the frame-supporting structure has a significant impact on the computed seismic reactions.

Keywords: tensile membrane structures, seismic excitations, dynamic analysis, finite element method

1 Introduction

The structural analysis and design of tensile membrane structures (TMS) is a subject that has become important in recent years and some methodologies and recommendations have arisen to cope with the complex behavior of these light weight structures with impressive designs. Noticeably, the TMS analysis and design concerns are focused on certain types of loads which are considered critical for fabric structures. Recent studies focus primarily in demands on TMS due to wind and snow loads to analyze the structures, to compute their reliability and to review other aspects (e.g., [1], [2], [3], [4], [5], [6], [7] and [8]).

The seismic response of TMSs is virtually absent in the literature, and recommended guidelines (e.g., [9]) and formal code regulations are still under development in many countries (e.g., [10]). Even though the wind and snow loads seem to capture the attention of more designers and studies on TMSs, it will be seen in the present work that consideration of the earthquake forces may be relevant for some specific issues regarding the seismic response of TMSs and their supporting structures.

Recent literature dealing with the analysis of TMSs is based on the finite element method (FEM), however detailed information on the employed programs is not always reported or commercial software is used ([1], [11], [5]); this is important, since there is a wide variability of results when using FEM to analyze TMSs ([5]). In the present study an on-purpose own developed code which accounts for wrinkling phenomena, orthotropic material modeling, and geometrical non-linearity is used, which formulation and discretization is established in detail in ([12]) and references within. [13] and [14] used a similar formulation.

Although there are TMSs with different shapes reported in the literature, the hyperbolic paraboloid, nicknamed as hypar, has become some sort of benchmark for TMS studies and is used by several authors in recent works (e.g., [1], [4], [6], [7], [8]). Hypar TMSs with different supporting sub structures are considered in the present study. Considering the preceding paragraphs, the main objective of this study is to assess the seismic response of hypar TMSs and their frame-supporting structure subjected to earthquake loads using our referred FEM code.

2 Finite Element Formulation

The finite element analysis formulation to be used for the dynamic analyses of membrane structures is based on a previous study [12], which is used for the structures under analysis in this study.

It is important to mention that fabric manufacturers usually do not provide in their catalogs the thickness of their membrane products, and they report only the tensile stiffness. This last parameter is enough to perform a static or quasi-static analysis. If the tensile stiffness is given and the formulation given in [12] is going to be used, some changes must be carried out. Because both alternatives could be of interest for researchers, and because the formulation given by [12] is versatile enough to implement any of the alternatives, a brief description is given in the following when no thickness is directly available.

First, it is noted that in [12] the internal forces are obtained by means of

${\displaystyle \mathbf {f} ^{\,{\hbox{int}}}=A_{0}\,t\,\mathbf {B} ^{T}\,\mathbf {Q} ^{T}\,\mathbf {T} _{\sigma }\,\mathbf {S} }$

(1)

where: ${\textstyle A_{0}}$ is the element surface in reference configuration, ${\textstyle t}$ is the membrane thickness, ${\textstyle \mathbf {B} }$ is the nonlinear strain-displacement matrix, ${\textstyle \mathbf {Q} }$ is the transformation matrix from a curvilinear system to a rectangular one, ${\textstyle \mathbf {T} _{\sigma }}$ is the rotation matrix from fiber axes to local axes, and S is the ${\textstyle 2^{nd}}$ Piola-Kirchhoff stress vector (force per unit area). In equation (1), the stresses are computed as

${\displaystyle \mathbf {S} =\mathbf {C} \cdot \mathbf {E} }$

(2)

where: ${\textstyle \mathbf {E} }$ is the Green-Lagrange strain vector, and the constitutive equation ${\textstyle \mathbf {C} }$ is expressed as

${\displaystyle \mathbf {C} ={\frac {E}{1-\nu ^{2}}}{\begin{bmatrix}1&\nu &0\\\\\nu &1&0\\\\0&0&{\dfrac {1-\nu }{2}}\end{bmatrix}}}$

(3)

In equation (3), ${\textstyle E}$ is the Young modulus and ${\textstyle \nu }$ is the Poisson coefficient. Since material properties given in most manufacturers' catalogs neither give a value for the thickness ${\textstyle t}$ nor for the Young modulus ${\textstyle E}$, then the internal forces for membrane analysis must be evaluated using

${\displaystyle \mathbf {f} ^{\,{\hbox{int}}}=A_{0}\,t\,\mathbf {B} ^{T}\,\mathbf {Q} ^{T}\,\mathbf {T} _{\sigma }\,\mathbf {S} ^{l}}$

(4)

where: ${\textstyle \mathbf {S} ^{l}}$ is the ${\textstyle 2^{nd}}$ Piola-Kirchhoff stress vector (force per unit length), and

${\displaystyle \mathbf {S} ^{l}=\mathbf {D} \cdot \mathbf {E} }$

(5)

with

${\displaystyle \mathbf {D} ={\frac {E_{ts}}{1-\nu ^{2}}}{\begin{bmatrix}1&\nu &0\\\\\nu &1&0\\\\0&0&{\dfrac {1-\nu }{2}}\end{bmatrix}}}$

(6)

where: ${\textstyle E_{ts}}$ is the tensile stiffness of the material, given in units of force per unit length (as usual in manufacturers of membrane materials). It is remarked that the tensile stiffness of the material is numerically equivalent to the Young modulus times the thickness, ${\textstyle E_{ts}=E\,t}$, therefore the thickness is no longer required as stated in the original formulation as given in [12].

For the case when an orthotropic material is modelled, two directions of the tensile stiffness must be given, which are ${\textstyle E_{w}}$ for the warp direction and ${\textstyle E_{f}}$ for the fill direction. Consequently, in the orthotropic plane stress constitutive equation, ${\textstyle E_{x}}$ must be replaced by ${\textstyle E_{w}}$, and ${\textstyle E_{y}}$ must be replaced by ${\textstyle E_{f}}$. If desired, these changes would allow us to solve other problems, for instance the numeric examples given in [5].

Unfortunately, the previous simplification is only valid for static or quasi-static analyses. For a dynamic seismic analysis to explicitly determine the thickness, ${\textstyle t}$, is necessary. Consequently, the original formulation in [12] is used, so that the right structure mass is accounted for and a consistent analysis assessing the internal forces given by equation (1) can be performed, which allows to complete the formulation with

${\displaystyle \mathbf {f} ^{\,int}+\mathbf {M} \mathbf {a} =\mathbf {f} ^{\,ext}}$

(7)

here, the external forces ${\textstyle \mathbf {f} ^{\,ext}}$ are given by the ${\textstyle 2^{nd}}$ Newton's law, by considering the seismic record as the acceleration for the studied site which is defined later. It is noteworthy that the formulation in [12] is of a wide applicability, and since it was originally developed to cope with dynamic analyses, it can be used to analyze the TMS under seismic excitations given below.

3 Examples

3.1 Structure 1

In this study a tensile-structure supported on a sub-structure is investigated. The geometry of the tensile-structure, as well as the surrounding cable along the perimeter, are shown in figure 1.

Figure 1: Membrane geometry and surrounding cable

In table 1 the values of the geometry of the tensile-structure and the surrounding cable are listed.

Table. 1 Membrane geometry

Node	x-Coord	y-Coord	z-Coord
${\textstyle 1}$	${\displaystyle 0.0}$	${\displaystyle 0.0}$	${\displaystyle 0.0}$
${\displaystyle 2}$	${\displaystyle 3.0}$	${\displaystyle 0.3}$	${\displaystyle 5.0}$
${\displaystyle 3}$	${\displaystyle 6.0}$	${\displaystyle 0.0}$	${\displaystyle 6.0}$
${\displaystyle 4}$	${\displaystyle 5.7}$	${\displaystyle 3.0}$	${\displaystyle 5.0}$
${\displaystyle 5}$	${\displaystyle 6.0}$	${\displaystyle 6.0}$	${\displaystyle 4.0}$
${\displaystyle 6}$	${\displaystyle 3.0}$	${\displaystyle 5.7}$	${\displaystyle 5.0}$
${\displaystyle 7}$	${\displaystyle 0.0}$	${\displaystyle 6.0}$	${\displaystyle 6.0}$
${\displaystyle 8}$	${\displaystyle 0.3}$	${\displaystyle 3.0}$	${\displaystyle 5.0}$
${\displaystyle 9}$	${\displaystyle -0.30945}$	${\displaystyle -0.30945}$	${\displaystyle 3.8299}$
${\displaystyle 10}$	${\displaystyle 6.30945}$	${\displaystyle -0.30945}$	${\displaystyle 6.1701}$
${\displaystyle 11}$	${\displaystyle 6.30945}$	${\displaystyle 6.30945}$	${\displaystyle 3.8299}$
${\displaystyle 12}$	${\displaystyle -0.30945}$	${\displaystyle 6.30945}$	${\displaystyle 6.1701}$

From the coordinates listed in table 1, it can be observed that the highest points for the membrane correspond to nodes 3 and 7, while the highest points for the cables correspond to nodes 10 and 12. The direction along the highest points is coincident with the principal direction of the fiber reinforcement of the membrane, i.e. the warp direction, also indicated in figure 1.

In figure 2 the nodes of the supporting sub-structure are shown.

Figure 2: Nodes and plan view of the supporting sub-structure

Coordinates for the geometry of the supporting sub-structure shown in figure 2 are listed in table 2.

Table. 2 Sub-structure geometry

Node	x-Coord	y-Coord	z-Coord
${\textstyle 13}$	${\displaystyle 1.1048}$	${\displaystyle 1.1048}$	${\displaystyle 0.0}$
${\displaystyle 14}$	${\displaystyle 4.8952}$	${\displaystyle 1.1048}$	${\displaystyle 0.0}$
${\displaystyle 15}$	${\displaystyle 4.8952}$	${\displaystyle 4.8952}$	${\displaystyle 0.0}$
${\displaystyle 16}$	${\displaystyle 1.1048}$	${\displaystyle 4.8952}$	${\displaystyle 0.0}$
${\displaystyle 17}$	${\displaystyle -2.30945}$	${\displaystyle -0.30945}$	${\displaystyle 0.0}$
${\displaystyle 18}$	${\displaystyle -0.30945}$	${\displaystyle -2.30945}$	${\displaystyle 0.0}$
${\displaystyle 19}$	${\displaystyle 6.3095}$	${\displaystyle -2.3095}$	${\displaystyle 0.0}$
${\displaystyle 20}$	${\displaystyle 8.3095}$	${\displaystyle -0.30945}$	${\displaystyle 0.0}$
${\displaystyle 21}$	${\displaystyle 8.3095}$	${\displaystyle 6.3095}$	${\displaystyle 0.0}$
${\displaystyle 22}$	${\displaystyle 6.3095}$	${\displaystyle 8.3095}$	${\displaystyle 0.0}$
${\displaystyle 23}$	${\displaystyle -0.30945}$	${\displaystyle 8.3095}$	${\displaystyle 0.0}$
${\displaystyle 24}$	${\displaystyle -2.3094}$	${\displaystyle 6.3094}$	${\displaystyle 0.0}$

The resulting mesh by using the previous listed membrane and support coordinates are depicted in figure 3 and, as it can be observed in the figure, consists of linear triangles with a ${\textstyle 20\times 20}$ mesh for the membrane. The cables and posts are defined by a two-noded unidimensional element. Both mentioned types of elements are Total Lagrangian non-linear geometric elements. Also, in figure 3 the control points A, B and C used for obtaining the displacements and stresses to be discussed later are shown.

Figure 3: Mesh and reference points for the studied structure

The material properties of the membrane, after [5], are listed in table 3, where a thickness for the membrane has been added.

Table. 3 Membrane properties

Tensile stiffness warp direction, ${\textstyle E_{w}}$	600.0 ${\textstyle kN/m}$
Tensile stiffness fill direction, ${\textstyle E_{f}}$	600.0 ${\textstyle kN/m}$
Shear stiffness, ${\textstyle G}$	30.0 ${\textstyle kN/m}$
Poisson, ${\textstyle v_{wf}=v_{fw}}$	0.1
Thickness, ${\textstyle t}$	1.0 ${\textstyle mm}$
Density, ${\textstyle \rho }$	1800.0 ${\textstyle kg/m^{3}}$

The cable, tensors and posts material properties can be found in table 4. Note that we denote post as a compression member in the supporting sub-structure (purple elements in figure 3), and tensor as a tension member of the supporting sub-structure (cyan elements in figure 3).

Table. 4 Sub-structure properties

	Young modulus	Cross section	Density
Cable	210 ${\textstyle GPa}$	${\displaystyle 0.127\times 10^{-3}}$${\textstyle m^{2}}$	7800 ${\textstyle kg/m^{3}}$
Tensor	210 ${\textstyle GPa}$	${\displaystyle 0.127\times 10^{-3}}$${\textstyle m^{2}}$	7800 ${\textstyle kg/m^{3}}$
Post	210 ${\textstyle GPa}$	${\displaystyle 4.748\times 10^{-3}}$${\textstyle m^{2}}$	8500 ${\textstyle kg/m^{3}}$

The structure is subjected to two load stages, and the wrinkling model described in [12] is used in both phases. The first stage corresponds to prestress, which is applied as per the values indicated in table 5.

Table. 5 Prestress properties

Membrane prestress: warp=fill	3.0 ${\textstyle kN/m}$
Cable prestress	2.36 ${\textstyle MN/m^{2}}$
Tensor prestress	1.18 ${\textstyle MN/m^{2}}$

The prestress stage in is turn divided into two parts as follows:

• Prestress

• A quasi-static analysis is carried out by applying the prestress linearly with a step time increment ${\textstyle \Delta t=0.01}$ for 100 steps. Subsequently, the load is sustained for 10 more steps until a relaxation of the structure is achieved.
• While keeping the prestress loads, we proceed to carry out a static non-linear analysis to find the right stationary solution by further applying five more steps.

The second load stage corresponds to the seismic loads, which are applied by using as input the accelerations of the 6.6 magnitude (Richter scale) earthquake recorded at Northern Norcia, Italy, on October 30, 2016 and shown in figure 4.

Figure 4: Accelerogram form the Norcia, Italy earthquake

The seismic loading is added to the resulting prestressing state in the second stage as follows:

• Prestress + Seismic load

• A seismic undamped dynamic analysis with a time step increment ${\textstyle \Delta t=0.005}$ ${\textstyle s}$ is performed up to a total of 8000 time steps equivalent to a duration of ${\textstyle 40}$ ${\textstyle s}$ of the earthquake record. In particular, the global X direction was analyzed by considering that the 100% of the earthquake acted along this direction

It is pointed out that for the case of a geometric non-linear dynamic analysis, Newmark's dynamic method does not provide a right solution; therefore, ${\textstyle \alpha {-}}$methods like the HHT [15], WBZ [16] or Generalized-${\textstyle \alpha }$ [17] are required.

The results from the dynamic analysis highlight important issues to be considered for these kinds of structures. To elaborate on this, first consider the largest displacement component at control point A depicted in figure 5. At this point the displacement due to prestress leads to a descend of the structure to a maximum of 2.9 mm, and from there the maximum absolute displacement during the earthquake further increases to a maximum of 10.9 mm. This is equivalent to a 375% increase, if the prestress displacement is used as reference. Even though such increase is significant in percentage, is not critical from a serviceability point of view for the structure, since the lowest point in the membrane is located at a 4 m height.

Figure 5: Displacement in the Z direction for control point A

To further elaborate on the discussion, the largest displacement component for control point B is shown in figure 6, where it can be observed that the structure raises to a maximum of 1.4 mm due to the prestress, and from there it further reaches a maximum absolute displacement of 5.9 mm during the earthquake. This is equivalent to a 421% increase, is the prestress displacement is used as reference.

Figure 6: Displacement in the Z direction for control point B

It is noted that by employing the same scale as in the previous two figures, the largest displacement component for control point C is in the X direction; however, for a consistent comparison (i.e. in the same direction as in the previous two figures) the displacement in the Z direction for control point C is shown in figure 7. At this point the displacement due to prestress leads to a descend of the structure to a maximum of 5.3 mm; during the earthquake the absolute maximum displacement is 4.5 mm.

Figure 7: Displacement in the Z direction for control point C

The displacement in the X direction for control point C is observed in figure 8; it is shown that the displacement due to prestress is practically zero (exactly 7.3x10-5 mm), and it reaches an absolute maximum of 5.5 mm during the earthquake.

Figure 8: Displacement in the X direction for control point C

From the previously described results it could be natural to expect similar increments in the membrane stresses. However, the stress increments in the membrane are not as significant; this is evidenced in figures 9 and 10. For the warp stress, the maximum increment due to the dynamic loads is located at point C and is equal to a static value of 1.76 kN/m, while the maximum dynamic value is equal to 1.92 kN/m. This means that the stress increase is in the order of 9.0%, considering the static value as reference. For the fill stress similar trends are found, being the maximum increase of the order of 8.5% located at point C (with static and dynamic values of 1.64 kN/m and 1.78 kN/m, respectively). In figures 9 and 10 the stresses at the other control points (A and B) are also indicated; similar trends can be observed but they are not included since their increments are lower than those of point C.

Figure 9: Stresses in the warp direction

Figure 10: Stresses in the fill direction

With the results discussed so far, one may think that the quantitative values of stresses and displacements due to earthquake loads are not that relevant for design purposes when membrane structures are considered (as opposed to the usually more critical values resulting from wind loading). However, a different story could be found if the design is focused on the foundation supports (anchorage) as will be discussed shortly after, and consequently care should be exercised by the designer in such a case.

In figures 11, 12 and 13 the most critical behavior at the structure foundation supports, corresponding respectively to nodes 16, 23 and 24 in figure 2, is shown. In figure 11, the static reaction in the Z direction is 57.8 kN, and the corresponding dynamic value is 63.1 kN; it means an increment of 9.1% in the compression force on the support.

Figure 11: Reactions at major post

Figure 12: Reactions at major tensor 1

Figure 13: Reactions at major tensor 2

In figure 12 the maximum response in the Z direction is exhibit, which is a tension force and is given by a negative value in the reaction; the static value of such response is -22.3 kN, while maximum absolute dynamic response is -31.5 kN, meaning that an increase of tension of 41% is found. Likewise, figure 13 shows that the maximum response is, one more time, a tensile force in the Z direction; this time the static value of such response is -22.3 kN, while maximum absolute dynamic response is -31.2 kN (i.e., a 40% increment).

Figure 14 shows the norm of the major reactions on the structure, which corresponds to node 23 in figure 2. It can be observed that the static response value is 23.5 kN, while the maximum dynamic response is 33.1 kN; a 40.9% increment. This increase is significant, since the usual design load factors do not cover such a large increment in terms of force.

Figure 14: Norm of reactions at major tensor 1

3.2 Structure 2

The increment in the reaction at the foundation supports during an earthquake may be generated by the horizontal component of the compression post due to the transmission of seismic horizontal forces to the structure. To investigate further this issue, the structure response is obtained by considering that the posts are not inclined, but oriented in the vertical direction. The new geometry with the changed nodes is shown in figure 15, and they are the nodes 13, 14, 15 and 16.

Figure 15: Updated geometry of the membrane and surrounding cable

For a better visual appreciation, the new structure can be observed in 3D in figure 16, where it can be readily observed that the posts are now vertical.

Figure 16: Updated geometry of the membrane and surrounding cable

In figure 17 the norm of the major reactions is shown for the new structure. It corresponds to node 23 in figure 15 and it can be observed that the static response has a value of 24.3 kN, while maximum absolute dynamic response is 44.6 kN, which represents a surprising 83.5% increment with respect to the static response. This value is enormous, and it is considered that no common factor in codified design accounts for such a large increment.

Figure 17: Norm of reactions at major tensor 1 for new geometry

It can be concluded that the increase in the reactions of the membrane foundation supports is very significant, this should be considered when designing the supports and posts orientations in seismic prone regions.

From the previous description of displacements and stresses and the discussion along, it can be concluded that although the seismic response of TMSs seems not to be considered important in the literature, care should be exercised in seismic regions when designing these kind of structures, because the displacements and support reactions increments can be relevant, and this highlights the necessity to verify that critical cases due to earthquake load are not reached. It is also concluded that the orientation of the elements on the supporting structure (e.g., the posts) can have an impact on the obtained forces at the foundation. Further research to investigate other geometries (in the TMS as well as in the supporting structure) and other seismic loads, as well as a comparison with other types of loading (e.g., wind loading) is strongly recommended.

4 Conclusions

The seismic response of hypar TMSs under seismic excitations is computed. A FEM which accounts for wrinkling phenomena, orthotropic material modeling, and geometrical non-linearity is employed for the dynamic analysis. Displacements, stresses and reactions are described for selected nodes. A record of a relatively large earthquake recorded at Northern Norcia, Italy, was used for the analyses. It is pointed out that the seismic response of TMSs is virtually absent in the specialized literature and that codes and standards are still under developments for these structures.

It was found that important increments are obtained in terms of displacements when the dynamic loads are considered, compared to the prestressed static loads. Although stress increments are not as large, the supports reactions exhibit a significant increment of the order of 40% (always compared versus the static case). Moreover, if the geometry of the supporting structure orientations is varied (e.g., inclined posts versus vertical posts) the increase at the reactions can be even higher (over 80%

It is highlighted that the seismic response of TMSs should be checked in seismic regions, because the displacements and support reactions increments can be significant, and possible critical cases due to earthquake load should be inspected. It is also pointed out that the orientation of the elements on the supporting structure (e.g., the posts) can have an important impact on the obtained forces at the foundation. Therefore, further studies considering other geometries in the TMS and in the supporting structure, other seismic loads and comparisons with other types of loading are strongly recommended.

5 Acknowledgements

We are grateful to Universidad de Guanajuato for its support and to the International Centre for Numerical Methods in Engineering (CIMNE) for providing us with the pre and post processor GiD [18] in our CIMNE-Classroom at the Civil Engineering Department.

BIBLIOGRAPHY

[1] Y. Zhang and Y. Lu and Y. Zhou and Q. Zhang. (2018) "Resistance uncertainty and structural reliability of hypar tensioned membrane structures with PVC coated polyesters", Volume 124. Thin-Walled Structures 392-401

[2] Subhrajit Dutta and Siddhartha Ghosh and Mandar M. Inamdar. (2017) "Reliability-based design optimization of free-supported tensile membrane structures", Volume 3(2). ASCE-ASME J. Risk Uncertainty Eng. Syst. G401600-1-G401600-11

[3] Subhrajit Dutta and Siddhartha Ghosh and Mandar M. Inamdar. (2018) "Optimisation of tensile membrane structures under uncertain wind loads using pce and kriging based metamodels", Volume 57. Struct. Multidisc. Optim. 1149-1161

[4] J. Colliers and M. Mollaert and J. Vierendeels and L. De Laet. (2016) "Collating wind data for doubly-curved shapes of tensioned surface structures (Round Robin Exercise 3)", Volume 155. International symposium on novel structural skins - improving sustainability and efficiency through new structural textile materials and designs 152-162

[5] P. D. Gosling and B.N. Bridgens and A. Albrecht and H. Alpermann and A. Angeleri and M. Barnes and N. Bartle and R. Canobbio and F. Dieringer and S. Gellin and W.J. Lewis and N. Mageau and R. Mahadevan and J.-M. Marion and P. Marsden and E. Milligan and Y.P. Phang and K. Sahlin and B. Stimpfle and O. Suire and J. Uhlemann. (2013) "Analysis and design of membrane structures: Results of a round robin exercise", Volume 48. Engineering Structures 313-328

[6] P. D. Gosling and B.N. Bridgens and L. Zhang. (2013) "Adoption of a reliability approach for membrane structure analysis", Volume 40. Structural Safety 39-50

[7] B. N. Bridgens and M. Birchall. (2012) "Form and function: The significance of material properties in the design of tensile fabric structures", Volume 44. Engineering Structures 1-12

[8] Fumiyoshi Takeda and Tatsuya Yoshino and Yasushi Uematsu. (2012) "Discussion of design wind force coefficients for hyperbolic paraboloid free roofs", Volume BBAA7. The Seventh International Colloquium on Bluff Body Aerodynamics and Applications 2-6

[9] B. Foster and M. Mollaert. (2004) "European design guide for tensile surface structures". TensiNet

[10] N. Stranghöner and J. Uhlemann and M. Mollaert. (2016) "Background to the science and policy report for tensile membrane structures", Volume 155. International symposium on novel structural skins - improving sustainability and efficiency through new structural textile materials and designs 256-264

[11] T. D. Dinh and A. Rezaei and S. Puystiens and M. Van Craenenbroeck and K. Carbonez and L. De Laet and M. Mollaert and D. Van Hemelrijck and W. Van Paepegem. (2015) "A study of tension fabric structures under in-plane loading: Nonlinear finite element analysis and validation", Volume 128. Composite Structures 10-20

[12] Jesús Gerardo Valdés-Vázquez and Juan Miquel Canet and Eugenio Oñate. (2009) "Nonlinear finite element analysis of orthotropic and prestressed membrane structures", Volume 45. Finite elements in Analysis and Design 395-405

[13] Riccardo Rossi and Massimiliano Lazzari and Renato Vitaliani and Eugenio Oñate. (2005) "Simulation of light-weight membrane structures by wrinkling model", Volume 62. International Journal for Numerical Methods in Engineering 2127-2153

[14] Roland Wüchner. (2006) "Mechanik und Numerik der Formfindung und Fluid-Struktur-Interaktion von Membrantragwerken". Technischen Universität München

[15] Hans M. Hilber and Thomas J. R. Hughes and Robert L. Taylor. (1977) "Improved numerical dissipation for time integration algoriths in structural dynamics", Volume 5. Earthquake Engineering and Structural Dynamics 283-292

[16] W. L. Wood and M. Bossak and O. C. Zienkiewics. (1980) "An alpha modification of Newmark's method", Volume 15. International Journal for Numerical Methods in Engineering 1562-1566

[17] J. Chung and G. M. Hulbert. (1993) "A time integration algorithm for structural dynamics with improved numerical dissipation: the generalized-${\textstyle \alpha }$ method", Volume 60. Journal of Applied Mechanics 371-375

[18]. (2017) "GiD – The personal pre and post processor". CIMNE, 13 Edition